How to Mill a Pocket on a Manual Mill

A pocket is one of the most common features you will mill, and on a manual mill, removing the material is the easy part. The hard part is stopping at the wall. The cut happens at the edge of the cutter, half a diameter away from the spindle, so for every wall you need to calculate where the spindle has to stop, and get the sign of the offset right. With four walls, a roughing pass and a finishing pass, the arithmetic adds up quickly, and a mistake usually costs the part.

This guide covers four ways to mill a pocket to size, starting with methods that work on any mill and ending with a pocket of any shape milled straight from a CAD drawing. All four use the same example pocket, so you can compare how much work each method leaves for you at the machine.

Before You Start

Some decisions are the same whichever method you use. The cutter sets the size of the corners, the depth of cut sets how many passes you need, and the direction you go around the walls decides how good the finish will be.

Choosing the Cutter

An end mill leaves its own radius in every inside corner, so the corner radius on the drawing limits the size of the cutter. To get a 1/8 in corner radius, for example, you need a cutter no larger than 1/4 in in diameter. A smaller cutter will work too, but then you need to mill the corner radius separately, or accept a sharper corner than the drawing calls for. If the pocket has square corners, the part will need a relief in each corner, or a file and some patience.

For the plunge, the cutter needs to be center cutting. Most two-flute and many four-flute end mills are, but some four-flute end mills aren't, and those can only enter the material from the side or through a starter hole.

Roughing and Finishing

When milling a pocket to size, it's best to leave a little material on the walls for a finishing pass, usually around 0.010 in (0.25 mm) per wall. A roughing pass deflects the cutter and leaves a rough wall, while a light finishing pass at full depth leaves a straight wall at the right size. It also gives you a chance to measure the pocket before the last cut, and correct the size if the cutter is cutting a little over or under its diameter.

Cutting Direction

On a manual mill, conventional milling is the safe default. In a climb cut, the cutter can pull the table into the backlash of the leadscrew, and the table can lurch forward and grab. With the spindle turning clockwise, as seen from above, conventional milling inside a pocket means going around the walls counterclockwise. Around the outside of a part, it is the other way around.

Getting to Depth

Unless the pocket is shallow, you will need more than one pass in Z. A reasonable starting point for an end mill on a hobby mill is a depth of cut of about half the cutter diameter, less in steel and more in aluminum. To start each level, plunge in the middle of the pocket and work outward to the walls. A starter hole drilled at the center of the pocket makes the plunge easier on the cutter, and it is the only way in for a cutter that isn't center cutting. For the floor, lock the quill or the knee at the final depth, and take the last pass at that depth all the way around.

The Example Pocket

Let's use a simple pocket to compare the methods: 1.500 in by 1.000 in, 0.250 in deep, with 1/8 in corner radii, in the top of a block. The pocket's lower-left corner is 0.500 in from the left and front edges of the block, and the block's lower-left corner is the X and Y zero. The cutter is a 1/4 in two-flute end mill, which leaves exactly the 1/8 in corner radius.

The walls of the pocket are at:

Left wall
X 0.500 in
Right wall
X 2.000 in
Front wall
Y 0.500 in
Back wall
Y 1.500 in

Before you start any of the methods, set the X and Y zero on the block's corner with an edge finder or a probe.

Method 1: Layout Lines

Layout lines are the traditional method, and they work for any pocket on any mill, with or without a DRO. To lay out the pocket, coat the top of the block with layout fluid and scribe the four walls with a height gauge, or with a scriber against a square. Then scribe the corner radii with dividers, or blend them by eye between the walls.

At the machine, rough the pocket to within about 1/32 in (0.8 mm) of the lines, watching the cutter against the layout. For the finishing pass, measure the remaining material with calipers and move the last bit with the handwheel dials, taking up the backlash in the same direction each time.

The method needs nothing more than a scriber, but it relies on your eye. A scribed line is a few thousandths of an inch wide, and the cutter hides the line just when you need to see it, so a pocket milled to layout lines is good to a few thousandths at best. It works well for clearance pockets and one-off parts where the size isn't critical. For a pocket that has to fit something, the finishing pass needs a measured number.

Method 2: Corner Coordinates in the DRO

With a DRO, you can work from numbers instead of lines. Most DRO consoles, TouchDRO included, have some form of sub-datum memory: a list of stored points, where selecting a point sets the X and Y readouts to the distance from the spindle to that point. If you store the four positions where the spindle has to stop, you can drive each readout to zero instead of watching a line.

The catch is that the stored points are positions of the spindle, not of the walls. For each corner, you need to move the point into the pocket by the cutter radius, and for the roughing pass, by the finish allowance as well. For the example pocket, the 1/4 in cutter has a 0.125 in radius, so the four positions are:

CornerFinishing passRoughing pass (0.010 in allowance)
Front leftX 0.625, Y 0.625X 0.635, Y 0.635
Front rightX 1.875, Y 0.625X 1.865, Y 0.635
Back rightX 1.875, Y 1.375X 1.865, Y 1.365
Back leftX 0.625, Y 1.375X 0.635, Y 1.365

Note that the offset goes the opposite way on opposite walls: you add the radius on the left and front walls and subtract it on the right and back walls. This is where the mistakes happen, and a sign error moves the wall by a full cutter diameter.

At the machine, select the first corner and crank X and Y to zero, then select the next corner and drive the axis that changes to zero, going around the pocket counterclockwise. Select the point before you move, and move only the axis that changes, since the readout of the other axis should already read zero. For the finishing pass, select the finishing points and go around once more. In TouchDRO, you can store the points as sub-datums, and select each one with a tap in the graphical view.

This method works on any DRO with point memory, and it is accurate, but it needs care. You need to calculate eight points, enter them without a typo, and select them in the right order, and nothing on the screen tells you that a point is wrong.

Method 3: Guide Lines in TouchDRO

For a rectangular pocket, TouchDRO's guide lines remove the arithmetic. A guide is a line on one axis, and when you activate it, the readout of that axis counts down to the line. With Tool Compensation on, the readout counts down to the edge of the cutter, so you place each guide on the wall itself, using the dimension from the drawing.

For the example pocket, add four guides at X 0.500 and X 2.000, and at Y 0.500 and Y 1.500, which are the four wall positions from the drawing. Then apply the 1/4 in cutter in Tool Compensation, with a finish allowance of 0.010 in for the roughing pass. To add a guide, long-press an empty area of the graphical view and choose "Add Guide".

With three more settings, you can let TouchDRO keep track of the rest:

  • With "Auto Tool Offset" on, activating a guide sets the cutter compensation to the side of the cutter that faces the guide, so the same cutter reads correctly against the left wall and the right one.
  • With the finish allowance set, the readout reaches zero with 0.010 in still left on the wall. For the finishing pass, clear the allowance in Tool Compensation and go around again.
  • With the automatic proximity warning on, TouchDRO beeps as the cutter gets close to the guide, so you can keep your eyes on the cut.

The step-by-step procedure, with the guides added relative to the current position, is in the "Cutting a Rectangular Pocket on a Mill" section of the manual. The method works for any pocket whose walls are parallel to the X and Y axes. For an angled wall, a curve, or a pocket with an island in it, you need the last method.

Method 4: Milling from a DXF Drawing

When the pocket isn't a rectangle, the stopping point changes with every move. On a curved or slanted wall, the X position where the cutter touches the wall depends on where Y is, so there is no single number to drive to. On a CNC mill, the CAM program calculates a toolpath for this. With TouchDRO, you can get much of the same help on a manual mill from the drawing itself.

To start, import the part's DXF drawing and place it on the part, as described in the "Machining to a CAD Drawing" guide. Apply the cutter in Tool Compensation, with the finish allowance for the roughing pass. Then tap the pocket's outline to select it, and tap the "Mill to Contour" button. TouchDRO will draw the area the cutter can reach in green, with the corners rounded to the cutter radius, and the X and Y readouts will show how far the cutter can travel along each axis before it touches the wall. To mill the pocket, crank one axis at a time and drive its readout to zero.

Because TouchDRO calculates the distance against the drawing's true lines and arcs, the number is right on slanted and curved walls too: it is the distance to the point where the edge of the cutter will touch, not to where the axis line crosses the wall. A dotted line shows you which wall each axis is measuring to, and with the automatic proximity warning on, the beep follows the axis you are cranking. If the pocket has an island in it, such as a boss you are milling around, tap the island's outline too before you turn the function on, since TouchDRO only treats a selected line as a wall.

The method works for any shape you can draw, including outlines: with the cutter outside a selected outline, TouchDRO guides the cut around the outside instead. Every control is described in the "Milling Pockets and Outlines from a Drawing" section of the manual.